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Introduction to Model Based Definition with Creo Parametric 7.0
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Reviewing Annotations and Combined States

Currently displayed annotations and model views can change for each combined state.

  • View manager

  • View tab

  • Quick Access toolbar

  • Annotate tab

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Figure 1 - 4_Notes Tab

Figure

Figure 2 - 7D Tab

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Figure 3 - 7B Tab

Reviewing Annotations and Combined States

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Figure 1 - 4_Notes Tab

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Figure 2 - 7D Tab

Figure

Figure 3 - 7B Tab The annotations that are currently displayed, along with the model view, can change for each combined state.

Each time a combined state is activated, the displayed annotations and model orientation can change. For example, you can configure notes and dimensions to appear or disappear while simultaneously reorienting the model whenever a particular combination state is activated.

Within each combined state, you can define the following:

  • Orientation — Select a saved view, or specify that the current model orientation be used as is.

  • Simplified representation — Enable a particular simplified rep.

  • Cross section — Display a specified cross-section.

  • Appearance — Display a specified appearance state.

  • Layers — Activate an existing layer state.

  • Visibility — Define the visibility of annotations and supplemental geometry.

Reviewing Annotations and Combined States

Close Window

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Erase Not Displayed

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Figure

MBD\Review_Annotations

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CONNECTOR_BRACKET_FULL.PRT

Steps

  • Task 1. Access combined states and Annotate mode. Enable only the following Datum Display types: Figure Figure

  • Click View Manager Figure from the In Graphics toolbar.

  • In the view manager, select the All tab. Notice the list of Combined States.

  • Scroll up if necessary and select 2_General . Right-click and select Activate Figure .

  • Notice the combined state appears as shown.

Figure

  • Select the Display combined views check box. Click Close .

  • Notice that tabs appear along the bottom of the graphics window. Select the 0_Model combined state tab.

  • Notice the combined state appears as shown.

Figure

  • In the ribbon, select the View tab. In the Model Display group, expand Manage Views .

  • Right-click Display Combined Views Figure and select Add to Quick Access toolbar .

  • Disable Display Combined Views Figure from the Quick Access toolbar.

  • Task 2. Review annotations belonging to the combined states. Select the Annotate tab. Select the 1_Map combined state tab.

  • Notice the 3-D notes referring to combined state tab names.

Figure

  • Press CTRL and select the 2_GENERAL INFORMATION note from the graphics window. Notice that the note hyperlinks directly to the 2_General combined state.

Figure

  • Select the 3_Properties combined state tab. Notice the use of parameters.

  • Cursor over the symbol in the center of the model. Figure

  • Select the 4_Notes combined state tab. Notice note 4 refers to a 3-D note, which in turn refers to a planar note on the model.

  • Cursor over note 5 and notice the added hyperlink to www.ptc.com. Figure

  • Select the 5_Datums combined state tab. Notice the GD&T Datums.

Figure

  • Select the 7A combined state tab. Notice the primary model dimensions.

Figure

  • Select the 7B combined state tab. Notice the profile dimensions, which include reference dimensions that are displayed in parentheses.

Figure

  • Select the 7C combined state tab. Notice the mounting hole dimensions.

Figure

  • Select the 7D combined state tab. Notice the cutout dimensions, which include GTOLs.

Figure

  • Select the Default All combined state tab. Figure

  • Task 3. View layer states. Click View Manager Figure . Select the Layers tab.

  • Notice the MBD-specific layer states.

Figure

  • Click Close in the view manager.

  • Task 4. Redefine a combined state to view its contents. Select the 7D combined state tab. Right-click and select Redefine .

  • Notice the defined orientation and layer state.

Figure

  • Click Cancel .